Rotary Roughing operation
Application Area:
Rotary Roughing is a continuous rough four-axis machining operation that removes the workpiece material layer by layer. It is similar to the Roughing Waterline operation except that the machining layers are not planes, but cylinders with their axis aligned along the Rotary Axis .
Job Assignment:
Top Level. Specifying the top level by model elements. This level defines the maximum radius on the model where machining happens. See more
Bottom Level. Specifying the bottom level by model elements. This level defines the minimum radius on the model where machining happens. See more
Properties. Displays the properties of an element. It is possible to add the stock. You can also call this menu by double clicking on an item in the list.
Delete. Removes an item from the list.
Strategy.
Job zone.
It enables additional modification of the working area initially selected on the Job Assignment tab.
Rotary axis. The system directs tool's axis vector from the designated Rotary Axis. The rotary axis position can be defined in the properties inspector. You can adjust the rotary axis interactively using the arrow or select it from the drop-down menu.
If the mode is set to the WCS X (GlobalCS X), WCS Y (GlobalCS Y) or WCS Z (GlobalCS Z), then the axis of rotation will be oriented along the corresponding axis of the coordinate system.
Direction. If mode is WCS (GlobalCS) (0,0,0) then axis vector must be defined manually in the fields X,Y,Z of custom direction group. Specify the direction cosines relative to each axis.
Origin. The Origin field defines the point that acts as the coordinate start for the chosen rotary axis .
Base CS. The Base Coordinate System (Base CS) changes the coordinate system between the global and local coordinate systems of the part.
Min. axial position. The minimum distance from the Origin along the axis of rotation. By default, it is taken from the workpiece.
Max. axial position. The maximum distance from the Origin along the axis of rotation. By default, it is taken from the workpiece.
Angular domain. This is an area defined by Start Angle and Finish Angle within which machining occurs. To change the job zone sizes you can mouse drag corresponding side of the visualized sector or specify the exact numerical value in the text box that appears next to dimension line.
Start angle. The initial angle of the sector.
Finish angle. The final angle of the sector.
Trajectory form.
The trajectory output format.
The trajectory can be in one of the following forms:
Linear. When you select this option, the work passes form as intersection lines between the machined surfaces and planes through the Rotary Axis. .
Circular. When you select this option, the work passes form as intersection lines between the machined surfaces and planes perpendicular to the Rotary Axis.
Spiral. Activating this option shapes the toolpath into a continuous helical line . The pattern is well suited for machining parts like screws and impellers.
Step. It is the distance between tool passes along the rotary axis.
Axial direction. Depending on the feature of the Trajectory Form parameter, it either defines the direction of the tool passes themselves or the sequence of several tool passes. In the case of a spiral whose step matches the machining Step, this parameter influences the direction of the spiral's twist .
Forward. The tool passes is ordered in the R otary Axis vector direction.
Backward. The tool passes are ordered in the reverse direction of the R otary Axis vector.
Spiral step. It defines parameters of the Spiral toolpath. The spiral step value can be positive or negative. The sign defines the torsion direction.
Same as the Basic Step. The toolpath is a single helix line.
mm, %Diameter, Angle. You can set it as an arbitrary value either as an absolute amount, as a percentage of the tool diameter, or as the angle of spiral twist in degrees. When the spiral step is not equivalent to the machining Step, a sequence of spiral paths occurs, spaced by the machining Step.
Angle by curve.
Automatically determines the helix angle based on the curve from the Job assignment.
Use flexible axis. When setting the flag, the system automatically determines the axis around which the working strokes are formed in each section as the average of the curvature centers in the section. This leads to a consistent trajectory that maintains continuity and corrects the orientation of the tool axis relative to the part. The option is suitable for asymmetric parts such as crankshafts
Milling Type.
Сan be assigned in almost all operations, except for the curve machining operations. This allows the user to control the required milling type (climb or conventional) during the toolpath calculation process. See more
The parameters of the Milling Type are the same. as in the Waterline Roughing operation. See more.
Sorting.
Controls the sequence of toolpath passes during surface machining.
By layers. The first layer of all profiles is machined in the beginning. After that the next layer is machined.
By strings. All levels of the first profile are machined first. After that all levels of the next profile are machined.
Offset.
The point towards which the tool is oriented can be offset from the Rotary Axis by the specified value . It can be specified to improve the cutting conditions. The offset can be defined as absolute value or as the percents of the tool diameter. It can be positive or negative.
Machining levels:
It defines the range along tool axis for the machining.
Depth Step. Material removed in one pass along the tool axis between the Top and Bottom levels. If the step is defined as the number of passes, the system will perform as many roughing passes as specified. If the step is defined by distance or as a percentage of the tool diameter, the system calculates the number of passes by dividing the allowance by the roughing Depth Step.
Uniform Step. Activating the flag causes the system to arrange depth passes to provide an even cutting depth within the allowed material removal.
Top level. The radius at which the first pass is made. By default it is the top most level of the machined part.
Bottom level. The radius at which the final pass is made. Drag the cylinder with the mouse and use 'Smart snap' to align with a feature to set the desired bottom level for machining. If the text in the field is green in colour, the level is calculated automatically as the bottom of the part, wokpiece and fixtures. To return to the automatic mode, simply clear the field and press 'Enter'.
Transformations:
Parameter's kit of operation, which allow to execute converting of coordinates for calculated within operation the trajectory of the tool. See more.