Rotary finishing
Application area:
The rotary machining operation is available if machine has at least one continuous rotary axis. It is used for the machining of the camshafts, crankshafts, worm shafts, paddles, decorate parts and so on. The main peculiarity of the operation is that it uses the 4th rotary axis together with the linear axes. The 5th axis (when it exists) is fixed. Sometimes the 5th axis can be used also. The Rotary machining operation gives the possibility to machine some surfaces of the part or the part as a whole. In the first case the required surfaces must be specified in the job assignment. In the second case the job assignment must be empty.
Job assignment:
Faces. Select various surfaces of the part as the working task. The system will calculate the trajectory based on the chosen surfaces.
Properties. Displays the properties of an element. It is possible to add the stock. You can also call this menu by double clicking on an item in the list.
Delete. Removes an item from the list.
Strategy.
Job zone.
It enables additional modification of the working area initially selected on the
Job assignment
tab.
Surface only. Machining occurs only on the selected surfaces.
With edges. The resulting toolpath features areas of machining selected surfaces as well as tool rolling sections on edges of selected surfaces .
With restriction model. The resulting toolpath features areas of machining selected surfaces, tool rolling sections on edges of selected surfaces, and areas with surfaces that form constraints .
Rotary axis. The system directs tool's axis vector from the designated Rotary Axis. The rotary axis position can be defined in the properties inspector. You can adjust the rotary axis interactively using the arrow or select it from the drop-down menu.
If the mode is set to the Along X, Along Y or Along Z, then the axis of rotation will be oriented along the corresponding axis of the coordinate system.
Direction. If mode is Custom(WCS) then axis vector must be defined manually in the fields X,Y,Z of custom direction group. Specify the direction cosines relative to each axis.
Origin. The Origin field defines the point that acts as the coordinate start for the chosen rotary axis .
Base CS. The Base Coordinate System (Base CS) changes the coordinate system between the global and local coordinate systems of the part.
Min. axial position. The minimum distance from the Origin along the axis of rotation. By default, it is taken from the workpiece.
Max. axial position. The maximum distance from the Origin along the axis of rotation. By default, it is taken from the workpiece.
Angular domain. This is an area defined by Start Angle and Finish Angle within which machining occurs. To change the job zone sizes you can mouse drag corresponding side of the visualized sector or specify the exact numerical value in the text box that appears next to dimension line.
Start angle. The initial angle of the sector.
Finish angle. The final angle of the sector.
Trajectory form.
The trajectory output format.
The trajectory can be in one of the following forms:
Linear. When you select this option, the work passes form as intersection lines between the machined surfaces and planes through the Rotary Axis. .
Circular. When you select this option, the work passes form as intersection lines between the machined surfaces and planes perpendicular to the Rotary Axis.
Spiral. Activating this option shapes the toolpath into a continuous helical line .
Step. Step along the rotary axis.
Axial direction. Depending on the feature of the Trajectory Form parameter, it either defines the direction of the tool passes themselves or the sequence of several tool passes . In the case of a spiral whose step matches the machining Step, this parameter influences the direction of the spiral's twist .
Forward. The tool passes is ordered in the R otary Axis vector direction.
Backward. The tool passes are ordered in the reverse direction of the R otary Axis vector.
Spiral step. It defines parameters of the Spiral toolpath. The spiral step value can be positive or negative. The sign defines the torsion direction.
Same as the Basic Step. The toolpath is a single helix line.
mm, %Diameter, Angle. You can set it as an arbitrary value either as an absolute amount, as a percentage of the tool diameter, or as the angle of spiral twist in degrees. When the spiral step is not equivalent to the machining Step, a sequence of spiral paths occurs, spaced by the machining Step.
Angle by curve. Automatically determines the helix angle based on the curve from the Job assignment.
Use flexible axis. When setting the flag, the system automatically determines the axis around which the working strokes are formed in each section a s the average of the curvature centers in the section. This leads to a consistent trajectory that maintains continuity and corrects the orientation of the tool axis relative to the part. The option is suitable for asymmetric parts such as crankshafts
Tool orientation.
Controls tool axis orientation.
Face. The tool axis is parallel to the surface normal in every tool path point in the plane perpendicular to the Rotary Axis.
Lead angle. It is a n additional tool tilt angle within the plane of motion direction. It allows to improve the cutting conditions in the contact point. It can be positive or negative.
Side angle. Specifies the inclination angle value of the tool axis relative to the axis designated as the Rotary Axis in the plane perpendicular to the motion direction.
To axis. The tool axis is intersect the rotary axis in every tool path point. So the tool axis does not depends on the surface normal.
Offset. The point towards which the tool is oriented can be offset from the Rotary Axis by the specified value . It can be specified to improve the cutting conditions. The offset can be defined as absolute value or as the percents of the tool diameter. It can be positive or negative.
Side angle. Specifies the inclination angle value of the tool axis relative to the axis designated as the Rotary Axis in the plane perpendicular to the motion direction .
Milling type.
Сan be assigned in almost all operations, except for the curve machining operations. This allows the user to control the required milling type (climb or conventional) during the toolpath calculation process. See more.
Sorting.
Controls the sequence of toolpath passes during surface machining.
By layers. The first layer of all profiles is machined in the beginning. After that the next layer is machined.
By strings. All levels of the first profile are machined first. After that all levels of the next profile are machined.
Idling minimization. If the flag is set, the system chooses each subsequent pass to minimize the links distance. When the flag is disabled, it processes all passes in a strict order determined by the machining directions and trajectory type .
Passes.
Defines the settings for rough and finish machining passes.
Rough passes. Setting the flag triggers the addition of roughing passes. You should specify the overall allowance for these passes in the text field.
Step. The step between rough passes. If the step is defined as the number of passes, the system will perform as many additional passes as specified. If the step is defined by distance or as a percentage of the tool diameter, the system calculates the number of passes by dividing the allowance by the roughing Step.
Finish pass. When the flag is set, the contour defined in the Job Assignment becomes the tool's finishing pass. The system adds an additional roughing pass at the entered distance. If Rough passes are in use, the final rough pass will take place at this entered distance.
Transformations:
Parameter's kit of operation, which allow to execute converting of coordinates for calculated within operation the trajectory of the tool. See more.
See also:
Operations for 4-axes and 5-axes milling